Methods Introduced:

The exception XToolkitDrawingCreateErrors is thrown if an error is encountered when creating a drawing from a template. This exception contains a list of errors which occurred during drawing creation.

The error structure contains an array of drawing creation errors. Each error message may have the following elements:

Use the method pfcExceptions.XToolkitDrawingCreateErrors.GetErrors to obtain the preceding array elements from the error object.

Method introduced:

Use the method wfcModelD.WModel2D.GetLocationGridColumnFromPosition and wfcModel.WModel2D.GetLocationGridRowFromPosition to find the grid coordinates of a location in the drawing. The method specifies the position of a point, expressed in screen coordinates. This method returns strings representing the row and column containing the point.

A Drawing Tree enables to view a hierarchical representation of drawing items in an active drawing sheet. A drawing tree facilitates selection and availability of drawing operations for the represented drawing items. For more information, see the Creo Parametric Help. Use the following functions to refresh, expand, and collapse the drawing tree:

Methods introduced:

Use the method wfcModel.WModel2D.CollapseTree to collapse all nodes of the drawing tree in the Creo Parametric window and make its child nodes invisible. The input argument WindowId returns the Id of the window which contains the drawing. Use-1 to expand the drawing tree in the active window.

Use the method wfcModel.WModel2D.ExpandTree to expand the drawing tree in the Creo Parametric window and make all drawing sheets and drawing items in the active drawing sheet visible.

Use the method wfcModel.WModel2D.RefreshTree to rebuild the drawing tree in the Creo Parametric window that contains the drawing. You can use this function after adding a single drawing item or multiple drawing items to a drawing.

Methods Introduced

Superseded Method:

The method wfcWDrawing.WDrawing.GetSheetName retrieves the name of the specified drawing sheet.

The method pfcSheet.SheetOwner.GetSheetTransform returns the transformation matrix for the sheet specified by the sheet number. This transformation matrix includes the scaling needed to convert screen coordinates to drawing coordinates (which use the designated drawing units).

The method pfcSheet.SheetOwner.GetSheetInfo returns sheet data including the size, orientation, and units of the sheet specified by the sheet number.

The method pfcSheet.SheetOwner.GetSheetData and the interfacepfcSheet.SheetData have been deprecated. Use the method pfcSheet.SheetOwner.GetSheetInfo and the interfacepfcSheet.SheetInfo instead.

The method pfcSheet.SheetOwner.GetSheetScale returns the scale of the drawing on a particular sheet based on the drawing model used to measure the scale. If no models are used in the drawing then the default scale value is 1.0.

The method pfcSheet.SheetOwner.GetSheetFormat returns the drawing format used for the sheet specified by the sheet number. It returns a null value if no format is assigned to the sheet.

The method pfcSheet.SheetOwner.GetSheetFormatDescr returns the model descriptor of the drawing format used for the specified drawing sheet.

The method wfcWDrawing.WDrawing.GetFormatSheet drawing format for a specified drawing and sheet number within the drawing . A drawing format file can have two sheets defining two formats. You can create drawings using either of the sheets as drawing format. If such a drawing format file is used to create the drawing, the method wfcWDrawing.WDrawing.GetFormatSheet retrieves the sheet number of the drawing format which was used to create the specified drawing.

The method pfcSheet.SheetOwner.GetSheetBackgroundView returns the view object representing the background view of the sheet specified by the sheet number.

The method pfcSheet.SheetOwner.GetNumberOfSheets returns the number of sheets in the model.

The method pfcSheet.SheetOwner.GetCurrentSheetNumber returns the current sheet number in the model.

The method pfcSheet.SheetOwner.GetSheetUnits returns the units used by the sheet specified by the sheet number.

Methods Introduced:

The method pfcSheet.SheetOwner.AddSheet adds a new sheet to the model and returns the number of the new sheet.

The method pfcSheet.SheetOwner.DeleteSheet removes the sheet specified by the sheet number from the model.

Use the method pfcSheet.SheetOwner.ReorderSheet to reorder the sheet from a specified sheet number to a new sheet number.

The method pfcSheet.SheetOwner.RegenerateSheet regenerates the sheet specified by the sheet number.

Use the method pfcSheet.SheetOwner.SetSheetScale to set the scale of a model on the sheet based on the drawing model to scale and the scale to be used. Pass the value of the DrawingModel parameter as null to select the current drawing model.

Use the method pfcSheet.SheetOwner.SetSheetFormat to apply the specified format to a drawing sheet based on the drawing format, sheet number of the format, and the drawing model.

The sheet number of the format is specified by the FormatSheetNumber parameter. This number ranges from 1 to the number of sheets in the format. Pass the value of this parameter as null to use the first format sheet.

The drawing model is specified by the DrawingModel parameter. Pass the value of this parameter as null to select the current drawing model.

The method pfcSheet.SheetOwner.SetCurrentSheetNumber sets the current sheet to the sheet number specified.

The method wfcModel.WModel2D.CopyDrawingSheet creates a copy of a specified drawing sheet. Specify the sheet number of the sheet to be copied in the input argument sheet. Set it to a value less than 1 to create a copy of the currently selected sheet.

Use the method wfcModel.WModel2D.ShowSheetFormat to display or hide the drawing format for a specified drawing sheet. The input arguments are :

The method wfcModel.WModel2D.GetToleranceStandard returns the tolerance standard that is assigned to the specified drawing.

Use the method wfcModel.WModel2D.SetToleranceStandard to set the tolerance standard for a drawing.

The method wfcModel.WModel2D.IsSheetFormatBlanked checks if the drawing format of a specified drawing sheet is blank. In case of the current sheet, set the input argument sheet to a value less than 1.

The method wfcModel.WModel2D.IsSheetFormatShown checks if the drawing format of a specified drawing sheet is shown. The output argument sheet returns the value as True, if the drawing format is shown and returns the value as False, if the drawing format is not shown.

The method wfcModel.WModel2D.CreateLeaderWithArrowTypeNote enables you to create a note with a leader and the specified arrow type in a specified drawing. The input arguments are:

The format of a drawing refers to the boundary lines, referencing marks and graphic elements that appear on every sheet before any drawing elements are shown or added. These usually include items such as tables for the company name, detailers name, revision number and date. In a Creo Parametric drawing, you can associate a format file (.frm) with the drawing. This file carries all the format graphical information, and it can also carry some optional default attributes like text size and draft scale. The functions described in this section allow you to get and set the size of the drawing format.

Methods Introduced:

The methods wfcModel.WModel2D.GetFormatSize and wfcModel.WModel2D.SetFormatSize retrieve and set the size of the drawing format in the specified drawing as awfcModel.FormatSizeData object. You can add a standard or customize size format in the drawing.

Use the method wfcModel.FormatSizeData_Create to create a drawing format in a specified drawing. The input arguments are:

The methods wfcModel.FormatSizeData.GetPaperSize and wfcModel.FormatSizeData.SetPaperSize get and set the size of the drawing using the enumerated data type pfcModel.PlotPaperSize.

The methods wfcModel.FormatSizeData.GetWidth and wfcModel.FormatSizeData.SetWidth get and set the width of the drawing.

The methods wfcModel.FormatSizeData.GetHeight and wfcModel.FormatSizeData.SetHeight get and set the height of the drawing.

Method Introduced:

The method pfcModel2D.Model2D.CreateView creates a new view in the drawing. Before calling this method, the drawing must be displayed in a window.

The interfacepfcView2D.View2DCreateInstructions contains details on how to create the view. The types of drawing views supported for creation are:

Methods Introduced:

The method pfcSelection.Selection.GetSelView2D returns the selected drawing view (if the user selected an item from a drawing view). It returns a null value if the selection does not contain a drawing view.

The method pfcModel2D.Model2D.List2DViews lists and returns the drawing views found. This method does not include the drawing sheet background views returned by the method pfcSheet.SheetOwner.GetSheetBackgroundView.

The method pfcModel2D.Model2D.GetViewByName returns the drawing view based on the name. This method returns a null value if the specified view does not exist.

The method pfcModel2D.Model2D.GetViewDisplaying returns the drawing view that displays a dimension. This method returns a null value if the dimension is not displayed in the drawing.

The method pfcSheet.SheetOwner.GetSheetBackgroundView returns the drawing sheet background views.

Methods Introduced:

The inherited method pfcObject.Child.GetDBParent, when called on a View2D object, provides the drawing model which owns the specified drawing view. The return value of the method can be downcast to a Model2D object.

The method pfcView2D.View2D.GetSheetNumber returns the sheet number of the sheet that contains the drawing view.

The method pfcView2D.View2D.GetIsBackground returns a value that indicates whether the view is a background view or a model view.

The method pfcView2D.View2D.GetModel returns the solid model displayed in the drawing view.

The method pfcView2D.View2D.GetScale returns the scale of the drawing view.

The method pfcView2D.View2D.GetIsScaleUserdefined specifies if the drawing has a user-defined scale.

The methodpfcView2D.View2D.GetOutline returns the position of the view in the sheet in world units.

The method pfcView2D.View2D.GetLayerDisplayStatus returns the display status of the specified layer in the drawing view.

The method pfcView2D.View2D.GetDisplay returns an output structure that describes the display settings of the drawing view. The fields in the structure are as follows:

The method pfcView2D.View2D.GetTransform returns a matrix that describes the transform between 3D solid coordinates and 2D world units for that drawing view. The transformation matrix is a combination of the following factors:

The method pfcView2D.View2D.GetName returns the name of the specified view in the drawing.

The simplified representations of assembly and part can be used as drawing models to create general views. Use the method pfcView2D.View2D.GetSimpRep to retrieve the simplified representation for the specified view in the drawing.

Methods Introduced:

The method wfcQuickPrint.wfcQuickPrint.DrawingViewDisplay_Create creates a new instance of the DrawingViewDisplay object that contains information about the display styles being used in a view.

The methods wfcQuickPrint.DrawingViewDisplay.GetCableDisp and wfcQuickPrint.DrawingViewDisplay.SetCableDisp get and set the style used to display the cables. You can set the cable style using the object wfcQuickPrint.CableDisplay:

In a view, you can define whether to show or hide the skeleton model. The methods wfcQuickPrint.DrawingViewDisplay.GetConceptModel and wfcQuickPrint.DrawingViewDisplay.SetConceptModel get and set the status of skeleton models. If you set the value as True, then the skeleton model is displayed.

The methods wfcQuickPrint.DrawingViewDisplay.GetDispStyle and wfcQuickPrint.DrawingViewDisplay.SetDispStyle get and set the display style of the model geometry. You can set the display style using the object pfcBase.DisplayStyle:

You can remove the hidden lines in a quilt. The methods wfcQuickPrint.DrawingViewDisplay.GetQuiltHLR and wfcQuickPrint.DrawingViewDisplay.SetQuiltHLR get and set the hidden line removal property in quilts.

The methods wfcQuickPrint.DrawingViewDisplay.GetTanEdgeDisplay and wfcQuickPrint.DrawingViewDisplay.SetTanEdgeDisplay get and set the display style for tangent edges. You can set the tangent edge display style using the object wfcQuickPrint.TangentEdgeDisplay:

You can show and hide the weld cross-sections in a drawing. The methods wfcQuickPrint.DrawingViewDisplay.GetWeldXSec and wfcQuickPrint.DrawingViewDisplay.SetWeldXSec get and set the display of weld cross-sections in a drawing.

Methods Introduced:

The method pfcView2D.View2D.SetScale sets the scale of the drawing view.

The method pfcView2D.View2D.Translate moves the drawing view by the specified transformation vector.

The method pfcView2D.View2D.Delete deletes a specified drawing view. Set the DeleteChildren parameter to true to delete the children of the view. Set this parameter to false or null to prevent deletion of the view if it has children.

The method pfcView2D.View2D.Regenerate erases the displayed view of the current object, regenerates the view from the current drawing, and redisplays the view.

The method pfcView2D.View2D.SetLayerDisplayStatus sets the display status for the layer in the drawing view.

The method pfcView2D.View2D.SetDisplay sets the value of the display settings for the drawing view.

Methods Introduced:

The method pfcModelItem.ModelItemOwner.ListItems returns a list of drawing dimensions specified by the parameter Type or returns null if no drawing dimensions of the specified type are found. This method lists only those dimensions created in the drawing.

The values of the parameter Type for the drawing dimensions are:

Set the parameter Type to the type of drawing dimension to retrieve. If this parameter is set to null, then all the dimensions in the drawing are listed.

The method pfcModelItem.ModelItemOwner.GetItemById returns a drawing dimension based on the type and the integer identifier. The method returns only those dimensions created in the drawing. It returns a null if a drawing dimension with the specified attributes is not found.

The method pfcSelect.Selection.GetSelItem returns the value of the selected drawing dimension.

Methods Introduced:

The methodpfcDimension2D.pfcDimension2D.DrawingDimCreateInstructions
_Create creates an instructions object that describes how to create a drawing dimension using the method pfcModel2D.Model2D.CreateDrawingDimension.

The parameters of the instruction object are:

The method pfcModel2D.Model2D.CreateDrawingDimension creates a dimension in the drawing based on the instructions data object that contains information needed to place the dimension. It takes as input an array of pfcSelection objects and an array of pfcDimensionSense structures that describe the required attachments. The method returns the created drawing dimension.

The method pfcDimension2D.pfcDimension2D.EmptyDimensionSense_Create creates a new dimension sense associated with the type DIMSENSE NONE. The sense field is set to Type In this case no information such as location or direction is needed to describe the attachment points. For example, if there is a single attachment which is a straight line, the dimension is the length of the straight line. If the attachments are two parallel lines, the dimension is the distance between them.

The method pfcDimension2D.pfcDimension2D.PointDimensionSense_Create creates a new dimension sense associated with the type DIMSENSE POINT which specifies the part of the entity to which the dimension is attached. The sense field is set to the value of the parameter PointType.

The possible values of PointType are:

The method pfcDimension2D.pfcDimension2D.SplinePointDimensionSense_Create creates a dimension sense associated with the type DIMSENSE_SPLINE_PT. This means that the attachment is to a point on a spline. The sense field is set to SplinePointIndex i.e., the index of the spline point.

The method pfcDimension2D.pfcDimension2D.TangentIndexDimensionSense_Create creates a new dimension sense associated with the type DIMSENSE_TANGENT_INDEX. The attachment is to a tangent of the entity, which is an arc or a circle. The sense field is set to TangentIndex, i.e., the index of the tangent of the entity.

The method pfcDimension2D.pfcDimension2D.LinAOCTangentDimensionSense_Create creates a new dimension sense associated with the type DIMSENSE_LINEAR_TO_ARC_OR_CIRCLE_TANGENT. The dimension is the perpendicular distance between the a line and a tangent to an arc or a circle that is parallel to the line. The sense field is set to the value of the parameter TangentType.

The possible values of TangentType are:

The method pfcDimension2D.pfcDimension2D.AngleDimensionSense_Create creates a new dimension sense associated with the type DIMSENSE_ANGLE. The dimension is the angle between two straight entities. The sense field is set to the value of the parameter AngleOptions.

The possible values of AngleOptions are:

The method pfcDimension2D.pfcDimension2D.PointToAngleDimensionSense_Create creates a new dimension sense associated with the type DIMSENSE_POINT_TO_ANGLE. The dimension is the angle between a line entity and the tangent to a curved entity. The curve attachment is of the type DIMSENSE_POINT_TO_ANGLE and the line attachment is of the type DIMSENSE POINT. In this case both the angle and the angle_sense fields must be set. The field sense shows which end of the curve the dimension is attached to and the field angle_sense shows the direction in which the dimension rotates and to which side of the tangent it attaches.

Methods Introduced:

The method pfcDrawing.Drawing.IsDimensionAssociative checks if the dimension or reference dimension is associative.

The method pfcDimension2D.Dimension2D.GetIsReference determines whether the drawing dimension is a reference dimension.

The method pfcDrawing.Drawing.IsDimensionDisplayed checks if the dimension is displayed in the drawing or solid.

The method pfcDrawing.Drawing.GetDimensionAttachPoints returns a sequence of attachment points for the dimension. The array of dimension senses returned by the method pfcDrawing.Drawing.GetDimensionSenses gives more information on how these attachments are interpreted. It gives information about how the dimension is attached to each attachment point of the model.

The method pfcDrawing.Drawing.GetDimensionSenses returns a sequence of dimension senses, describing how the dimension is attached to each attachment returned by the method pfcDrawing.Drawing.GetDimensionAttachPoints.

The method pfcDrawing.Drawing.GetDimensionOrientHint returns the orientation of the dimensions in case where this cannot be deduced from the attachment themselves. The orientation of the dimensions is given by the enumerated type pfcDimension.DimOrientationHint. The orientation determines how Creo will orient the dimension with respect to the attachment points.

The method pfcDrawing.Drawing.GetBaselineDimension returns an ordinate baseline drawing dimension. It returns a null value if the dimension is not an ordinate dimension.

The method pfcDrawing.Drawing.GetDimensionLocation returns the placement location of the dimension.

The method pfcDrawing.Drawing.GetDimensionView returns the drawing view in which the dimension is displayed. For dimensions created in drawing mode and owned by a solid, which can be displayed only in the context of that drawing, the method returns the drawing view. The method returns NULL if the dimension is not attached to a drawing view.

The method pfcDimension2D.Dimension2D.GetTolerance retrieves the upper and lower tolerance limits of the drawing dimension in the form of the pfcDimension.DimTolerance object. A null value indicates a nominal tolerance.

The method pfcDrawing.Drawing.IsDimensionToleranceDisplayed checks if the dimension tolerance is displayed in the drawing or solid.

The method wfcWDrawing.WDrawing.GetDimensionPath extracts the component path for a dimension displayed in a drawing.

The method wfcWDrawing.WDrawing.GetDualDimensionOptions retrieves information about the various options of dual dimensioning in a drawing as a wfcWDrawing.DualDimensionGlobalOptions object.

Use the method wfcDrawing.DualDimensionGlobalOptions.GetDualDimensionType to get the display style of dual dimensions. The display type is given by the enumerated type wfcDrawing.DualDimensionDisplayType. The valid values are:

Use the method wfcWDrawing.DualDimensionGlobalOptions.GetSecondaryUnit to retrieve the type of units used for the secondary dimension.

The method wfcWDrawing.DualDimensionGlobalOptions.GetDigitsDifference retrieves the number of decimal places that a secondary dimension contains as compared to the primary dimension in a dual dimension.

The method wfcWDrawing.DualDimensionGlobalOptions.AreBracketsAllowed checks if one of the dimensions of a dual dimension is displayed in brackets.

Methods Introduced:

The method pfcDrawing.Drawing.ConvertOrdinateDimensionToLinear converts an ordinate dimension to a linear dimension. The drawing or solid containing the dimension must be displayed.

The method pfcDrawing.Drawing.ConvertLinearDimensionToOrdinate converts a linear drawing dimension to an ordinate baseline dimension.

The method pfcDimension2D.Dimension2D.SetLocation sets the placement location of a dimension or reference dimension in a drawing or solid.

The method pfcDrawing.Drawing.SwitchDimensionView changes the view where a dimension created in the drawing or solid is displayed.

The method pfcDrawing.Drawing.EraseDimension permanently erases the dimension from the drawing or solid.

The method pfcModel2D.Model2D.SetViewDisplaying changes the view where a dimension created in a solid model is displayed.

Methods Introduced:

The method wfcSolid.WSolid.CreateOrdinateDimension creates a new model ordinate driven dimension or a model ordinate reference dimension in a solid model. It requires the input of a reference baseline annotation as well as a geometry reference. The annotation plane for the new dimension will be inherited from the baseline. Once the reference dimension is created, use the method wfcAnnotation.Annotation.ShowInDrawing to display it.

Method Introduced:

The method pfcTable.pfcTable.TableCell_Create creates the TableCell object representing a cell in the drawing table.

Some drawing table methods operate on specific drawing segment. A multisegmented drawing table contains 2 or more areas in the drawing. Inserting or deleting rows in one segment of the table can affect the contents of other segments. Table segments are numbered beginning with 0. If the table has only a single segment, use 0 as the segment id in the relevant methods.

Methods Introduced:

Tables may be selected using the method pfcSession.BaseSession.Select. Pass the filter dwg_table to select an entire table and the filter table_cell to prompt the user to select a particular table cell.

The method pfcSelect.Selection.GetSelItem returns the selected table handle. It is a model item that can be cast to a Table object.

The method pfcSelect.Selection.GetSelTableCell returns the row and column indices of the selected table cell.

The method pfcSelect.Selection.GetSelTableSegment returns the table segment identifier for the selected table cell. If the table consists of a single segment, this method returns the identifier 0.

Methods Introduced:

The method pfcTable.pfcTable.TableCreateInstructions_Create creates the TableCreateInstructions data object that describes how to construct a new table using the method pfcTable.TableOwner.CreateTable.

The parameters of the instructions data object are:

The method pfcTable.TableOwner.CreateTable creates a table in the drawing specified by the TableCreateInstructions data object.

Methods Introduced

The method pfcTable.TableOwner.RetrieveTable retrieves a table specified by the TableRetrieveInstructions data object from a file on the disk. It returns the retrieved table. The data object contains information on the table to retrieve and is returned by the method pfcTable.pfcTable.TableRetrieveInstructions_Create.

The method pfcTable.pfcTable.TableRetrieveInstructions_Create creates the TableRetrieveInstructions data object that describes how to retrieve a drawing table using the methods pfcTable.TableOwner.RetrieveTable and pfcTable.TableOwner.RetrieveTableByOrigin. The method returns the created instructions data object.

The parameters of the instruction object are:

You can also set the parameters for TableRetrieveInstructions data object using the following method:

The method pfcTable.TableOwner.RetrieveTable retrieves a table specified by the TableRetrieveInstructions data object from a file on the disk. It returns the retrieved table. The upper-left corner of the table is placed on the drawing sheet at the position specified by the TableRetrieveInstructions data object.

The method pfcTable.TableOwner.RetrieveTableByOrigin also retrieves a table specified by the TableRetrieveInstructions data object from a file on the disk. The origin of the table is placed on the drawing sheet at the position specified by the TableRetrieveInstructions data object. Tables can be created with different origins by specifying the option Direction, in the Insert Table dialog box.

Methods Introduced:

The method pfcTable.TableOwner.ListTables returns a sequence of tables found in the model.

The method pfcTable.TableOwner.GetTable returns a table specified by the table identifier in the model. It returns a null value if the table is not found.

The method pfcTable.Table.GetRowCount returns the number of rows in the table.

The method pfcTable.Table.GetColumnCount returns the number of columns in the table.

The method pfcTable.Table.CheckIfIsFromFormat checks if the drawing table was created using the format. The method returns a true value if the table was created by applying the drawing format.

The method pfcTable.Table.GetRowSize returns the height of the drawing table row specified by the segment identifier and the row number.

The method pfcTable.Table.GetColumnSize returns the width of the drawing table column specified by the segment identifier and the column number.

The method pfcTable.Table.GetText returns the sequence of text in a drawing table cell. Set the value of the parameter Mode to DWGTABLE_NORMAL to get the text as displayed on the screen. Set it to DWGTABLE_FULL to get symbolic text, which includes the names of parameter references in the table text.

The method pfcTable.Table.GetCellNote returns the detail note item contained in the table cell.

Methods Introduced:

The method pfcTable.Table.Erase erases the specified table temporarily from the display. It still exists in the drawing. The erased table can be displayed again using the method pfcTable.Table.Display. The table will also be redisplayed by a window repaint or a regeneration of the drawing. Use these methods to hide a table from the display while you are making multiple changes to the table.

The method pfcTable.Table.RotateClockwise rotates a table clockwise by the specified amount of rotation.

The method pfcTable.Table.InsertRow inserts a new row in the drawing table. Set the value of the parameter RowHeight to specify the height of the row. Set the value of the parameter InsertAfterRow to specify the row number after which the new row has to be inserted. Specify 0 to insert a new first row.

The method pfcTable.Table.InsertColumn inserts a new column in the drawing table. Set the value of the parameter ColumnWidth to specify the width of the column. Set the value of the parameter InsertAfterColumn to specify the column number after which the new column has to be inserted. Specify 0 to insert a new first column.

The method pfcTable.Table.MergeRegion merges table cells within a specified range of rows and columns to form a single cell. The range is a rectangular region specified by the table cell on the upper left of the region and the table cell on the lower right of the region.

The method pfcTable.Table.SubdivideRegion removes merges from a region of table cells that were previously merged. The region to remove merges is specified by the table cell on the upper left of the region and the table cell on the lower right of the region.

The methods pfcTable.Table.DeleteRow and pfcTable.Table.DeleteColumn delete any specified row or column from the table. The methods also remove the text from the affected cells.

The method pfcTable.Table.SetText sets text in the table cell.

Use the method pfcTable.TableOwner.DeleteTable to delete a specified drawing table from the model permanently. The deleted table cannot be displayed again.

The method wfcTable.WTable.GetGrowthDirection and wfcTable.WTable.SetGrowthDirection gets and sets the growth direction of the table using the enumerated type wfcTable.TableGrowthDirType.

The valid values for growth direction are defined in the enumerated data type wfcTable.TableGrowthDirType:

The methods wfcTable.WTable.GetRowHeightAutoAdjustType and wfcTable.WTable.SetRowHeightAutoAdjustType get and set the automatic row height adjustment property for a row of a drawing table. The type of height adjustment property is defined in the enumerated data type wfcTable.RowheightAutoadjustType:

The method wfcTable.WTable.Save saves a drawing table in different formats. The formats given by the enumerated type wfcTable.TableFormatType can be of the following types:

The methods wfcTable.WTable.SetColumnWidth and wfcTable.WTable.SetRowHeight assign the width of a specified column and the height of a specified row depending upon the size of the drawing table. The drawing table size given by the enumerated data type pfcTable.TableSizeType:

The method wfcTable.WTable.WrapCelltext wraps the text in a cell.

Drawing tables can be constructed with one or more segments. Each segment can be independently placed. The segments are specified by an integer identifier starting with 0.

Methods Introduced:

The method pfcSelect.Selection.GetSelTableSegment returns the value of the segment identifier of the selected table segment. It returns a null value if the selection does not contain a segment identifier.

The method pfcTable.Table.GetSegmentCount returns the number of segments in the table.

The method pfcTable.Table.GetSegmentSheet determines the sheet number that contains a specified drawing table segment.

The method pfcTable.Table.MoveSegment moves a drawing table segment to a new location. Pass the co-ordinates of the target position in the format x, y, z=0.

To get information about a drawing table pass the value of the segment identifier as input to the method pfcTable.Table.GetInfo. The method returns the table information including the rotation, row and column information, and the 3D outline.

Use the method wfcTable.WTable.SetSegmentOrigin to set the origin for a specified drawing table segment.

The method wfcTable.WTable.GetSegmentExtents returns the start and end rows and columns of a specified table segment. The input argument SegmentId is the table segment ID. Pass the value as -1 if you are referring to the only segment of a one-segment table.

The methods wfcTable.SegmentExtents.GetFirstColumn and wfcTable.SegmentExtents.GetFirstRow returns the first row and first column of a table segment.

The methods wfcTable.SegmentExtents.GetLastColumn and wfcTable.SegmentExtents.GetLastRow returns the last row and last column of a table segment.

Methods Introduced:

The methods pfcTable.Table.IsCommentCell, pfcTable.Table.GetCellComponentModel, pfcTable.Table.GetCellReferenceModel, pfcTable.Table.GetCellTopModel, and pfcTable.TableOwner.UpdateTables apply to repeat regions in drawing tables.

The method pfcTable.Table.IsCommentCell tells you whether a cell in a repeat region contains a comment.

The method pfcTable.Table.GetCellComponentModel returns the path to the assembly component model that is being referenced by a cell in a repeat region of a drawing table. It does not return a valid path if the cell attribute is set to NO DUPLICATE or NO DUPLICATE/LEVEL.

The method pfcTable.Table.GetCellReferenceModel returns the reference component that is being referred to by a cell in a repeat region of a drawing table, even if cell attribute is set to NO DUPLICATE or NO DUPLICATE/LEVEL.

The method pfcTable.Table.GetCellTopModel returns the top model that is being referred to by a cell in a repeat region of a drawing table, even if cell attribute is set to NO DUPLICATE or NO DUPLICATE/LEVEL.

Use the method pfcTable.TableOwner.UpdateTables to update the repeat regions in all the tables to account for changes to the model. It is equivalent to the command Table, Repeat Region, Update.

Methods Introduced:

The method wfcView2D.WView2D.GetParentView retrieves the parent view of a specified drawing view.

The method wfcView2D.WView2D.GetChildren retrieves the child views of a drawing view.

The method wfcView2D.WView2D.GetProjectionArrow checks if the projection arrow flag has been set for a projected or detailed drawing view.

The method wfcView2D.WView2D.GetPerspectiveScaleEyePointDistance retrieves the eye-point distance from model space for the perspective scale applied to a drawing view. This scale option is available only for general views.

The method wfcView2D.WView2D.GetPerspectiveScaleViewDiameter specifies the view diameter in paper units such as mm for the perspective scale applied to a drawing view. This scale option is available only for general views.

The method wfcView2D.WView2D.GetColorSource retrieves information about color designation of the drawing view using the enumerated type wfcView2D.DrawingViewColorSource. The valid values are:

The method GetColorSource retrieves the reference of the Z-clipping on the drawing view. The reference can be an edge, datum, or point on the surface that is parallel to the view. Geometry contained in the Z-clipping plane and in front of the plane appears, but geometry behind the plane does not appear. The system clips geometry that intersects the plane.

The method wfcView2D.WView2D.GetViewType retrieves the type of a specified drawing view using the enumerated data type wfcView2D.ViewType. A drawing view can be of the following types:

The method wfcView2D.WView2D.GetViewId retrieves the ID of the drawing view.

The method wfcView2D.WView2D.IsErased checks if the drawing view is erased or not. When you erase a view, it is removed from display in the drawing. The view is not deleted from the drawing.

The methods wfcView2D.WView2D.GetAlignmentInstructions and wfcView2D.WView2D.SetAlignmentInstructions retrieve and set the alignment of a drawing view with respect to a reference view as a wfcView2D.ViewAlignmentInstructions object.

The method wfcView2D.wfcView2D.ViewAlignmentInstructions_Create creates a data object that contains information about view alignment.

The methods wfcView2D.ViewAlignmentInstructions.GetReferenceView and wfcView2D.ViewAlignmentInstructions.SetReferenceView retrieve and set the reference view to which the drawing view is aligned.

The methods wfcView2D.ViewAlignmentInstructions.GetAlignmentStyle and wfcView2D.ViewAlignmentInstructions.SetAlignmentStyle get and set the alignment style using the enumerated type wfcView2D.DrawingViewAlignStyle. The valid values are:

The methods wfcView2D.ViewAlignmentInstructions.GetViewReference and wfcView2D.ViewAlignmentInstructions.SetViewReference get and set the geometry, such as an edge, on the reference view. The view is aligned along this geometry. If no geometry is specified, the reference view is aligned according to its view origin.

The methods wfcView2D.ViewAlignmentInstructions.GetAlignedViewReference and wwfcView2D.ViewAlignmentInstructions.SetAlignedViewReference get and set the geometry, such as an edge, on the drawing view. If no geometry is specified, the drawing view is aligned according to its view origin.

The method wfcView2D.WView2D.GetOriginSelectionRef retrieves the selection reference as a pfcSelect.Selection object for the drawing view.

The method wfcView2D.WView2D.GetOrigin retrieves the location of the origin as a pfcBase.Point3D object for the drawing view.

The method wfcView2D.WView2D.GetDatumDisplayStatus checks if a solid model datum has been explicitly shown in a particular drawing view using the enumerated type wfcView2D.ViewItemdisplayStatus. The valid values are:

The method wfcView2D.WView2D.GetPipingDisplay retrieves the piping display option for a drawing view using the enumerated type wfcView2D.PipingDisplay. The valid values are:

The method wfcView2D.WView2D.GetErasedViewSheet retrieves the sheet number which contained the view that was erased. If the sheet that contained the erased view is deleted, an exception is thrown.

The method wfcDrawing.WDrawing.NeedsRegen checks whether the drawing or the specified drawing view needs to be regenerated.

The method wfcDrawing.WDrawing.GetDrawingView retrieves the drawing view handle for the specified view ID.

The method wfcSession.WSession.OpenDrawingAsReadOnly opens a drawing in the view only mode.

Methods Introduced:

The method wfcView2D.WView2D.SetViewAsProjection assigns the specified drawing view as a projection.

The method wfcView2D.WView2D.SetProjectionArrow sets the projection arrow flag to true for a projected or detailed drawing view.

The method wfcView2D.WView2D.SetZClippingReference sets the Z-clipping on the drawing view to reference a given edge, datum, or point on the surface that is parallel to the view. Geometry contained in the Z-clipping plane and in front of the plane appears, but geometry behind the plane does not appear. The system clips geometry that intersects the plane.

The method wfcView2D.WView2D.Erase removes the specified drawing view from display. To display the view back in the drawing, use the method wfcView2D.WView2D.Resume.

The method wfcView2D.WView2D.SetOrigin assigns the location of the origin as a pfcBase.Point3D object and the selection reference for a specified drawing view as a pfcSelect.Selection object. Both the input arguments OriginLocation and Reference are optional. However, to set the origin successfully, you must pass a valid value to either of the input arguments. If you pass both the input arguments as Null, the method throws an exception pfcExceptions.XToolkitBadInputs.

The method wfcView2D.WView2D.SetPipingDisplay assigns the piping display option for a drawing view using the enumerated data type wfcView2D.PipingDisplay.

Methods Introduced:

A detailed view is a small portion of a model shown enlarged in another view.

The method wfcDrawing.WDrawing.CreateDetailView creates a detailed view given the reference point on the parent view, the spline curve data, and location of the new view. A note with the detailed view name and the spline curve border are included in the parent view for the created detailed view. The input arguments are:

Use the methods wfcView2D.WView2D.GetDetailViewInstructions and wfcView2D.WView2D.SetDetailViewInstructions to get and set the information related to detailed views as a wfcView2D.DetailViewInstructions object.

The method wfcView2D.wfcView2D.DetailViewInstructions_Create creates a data object that contains information about the detailed view.

Use the methods wfcView2D.DetailViewInstructions.GetReference and wfcView2D.DetailViewInstructions.SetReference to get and set the reference point on the parent view for a specified detailed view.

Use the methods wfcView2D.DetailViewInstructions.GetCurveData and wfcView2D.DetailViewInstructions.SetCurveData to get and set the spline curve data as a pfcGeometry.CurveDescriptor object for the specified detailed view. The information about the curve geometry is returned using the enumerated data type pfcGeometry.CurveType. The curve data specifies the following:

The methods wfcView2D.DetailViewInstructions.GetBoundaryType and wfcView2D.DetailViewInstructions.SetBoundaryType get and set the boundary type for a detailed view in terms of the enumerated type wfcView2d.ViewDetailBoundaryType. The types of boundaries are:

The method wfcView2D.DetailViewInstructions.ShowBoundary displays the boundary of the detailed view in the parent view.

The method wfc2View2D.DetailViewInstructions.IsBoundaryShown checks if the boundary of the detailed view is displayed in the parent view.

Methods Introduced:

An auxiliary view is a type of projected view that projects at right angles to a selected surface or axis. The selected surface or axis in the parent view must be perpendicular to the plane of the screen.

The method wfcDrawing.WDrawing.CreateAuxiliaryView creates an auxiliary view. Pass the information required to create the auxiliary view as a wfcView2D.AuxiliaryViewInstructions object.

The method wfcView2D.WView2D.GetAuxiliaryViewInstructions retrieves information about the auxiliary view as a wfcView2D.AuxiliaryViewInstructions object.

The method wfcView2D.wfcView2D.AuxiliaryViewInstructions_Create creates a data object that contains information about the auxiliary view.

The methods wfcView2D.AuxiliaryViewInstructions.GetReference and wfcView2D.AuxiliaryViewInstructions.SetReference retrieve and set the selection reference for the auxiliary view as a pfcSelect.Selection object.

The methods wfcView2D.AuxiliaryViewInstructions.GetLocation and wfcView2D.AuxiliaryViewInstructions.SetLocation retrieve and set the centerpoint of the auxiliary view as a pfcBase.Point3D object. By default, the origin of a drawing view is in the center of its outline. You can reset the origin of a drawing view by parametrically referencing model geometry or defining a location on the drawing sheet.

The method wfcView2D.WView2D.SetViewAsAuxiliary sets a specified drawing view as the auxiliary view.

Methods Introduced:

A revolved view is a cross section of an existing view, revolved 90 degrees around a cutting plane projection.

The method wfcDrawing.WDrawing.CreateRevolveView creates a revolved view given a cross section, the selection reference, and the point location. Pass the information required to create the auxiliary view as a wfcView2D.RevolveViewInstructions object.

The method wfcView2D.WView2D.GetRevolveViewInstructions retrieves information about the revolved view as a wfcView2D.RevolveViewInstructions object.

The method wfcView2D.wfcView2D.RevolveViewInstructions_Create creates a data object that contains information about the revolved view.

The methods wfcView2D.RevolveViewInstructions.GetReference and wfcView2D.RevolveViewInstructions.SetReference retrieve and set the selection reference for the revolved view as a pfcSelect.Selection object.

The methods wfcView2D.RevolveViewInstructions.GetXSec and wfcView2D.RevolveViewInstructions.SetXSec retrieve and set the cross section of the revolved view as a pfcXSection.XSection object.

The methods wfcView2D.RevolveViewInstructions.GetLocation and wfcView2D.RevolveViewInstructions.SetLocation retrieve and set the centerpoint of the revolved view as a pfcBase.Point3D object. By default, the origin of a drawing view is in the center of its outline. You can reset the origin of a drawing view by parametrically referencing model geometry or defining a location on the drawing sheet.

Methods Introduced:

The method wfcView2D.WView2D.SetOrientation orients the specified drawing view using saved views from the model. The input arguments are:

The method wfcView2D.WView2D.SetOrientationFromReference orients the view using geometric references.